DEMO_febio_0012_disc_pressure

Below is a demonstration for:

Building geometry for a thin disc with tetrahedral elements
Defining the boundary conditions
Coding the febio structure
Running the model
Importing and visualizing the displacement and stress results

Keywords
Plot settings
Control parameters
Creating model geometry and mesh
Defining the boundary conditions
Defining the FEBio input structure
Quick viewing of the FEBio input file structure
Exporting the FEBio input file
Running the FEBio analysis
Import FEBio results

Keywords

febio_spec version 4.0
febio, FEBio
pressure loading
tetrahedral elements, hex4
tetgen
disc
static, solid
hyperelastic, Ogden
displacement logfile
stress logfile

clear; close all; clc;

Plot settings

fontSize=20;
faceAlpha1=0.8;
markerSize=30;
markerSize2=20;
lineWidth=3;

Control parameters

% Path names
defaultFolder = fileparts(fileparts(mfilename('fullpath')));
savePath=fullfile(defaultFolder,'data','temp');

% Defining file names
febioFebFileNamePart='tempModel';
febioFebFileName=fullfile(savePath,[febioFebFileNamePart,'.feb']); %FEB file name
febioLogFileName=[febioFebFileNamePart,'.txt']; %FEBio log file name
febioLogFileName_disp=[febioFebFileNamePart,'_disp_out.txt']; %Log file name for exporting displacement
febioLogFileName_stress=[febioFebFileNamePart,'_stress_out.txt']; %Log file name for exporting stress

%Load
appliedPressure=0.5e-3;
loadType='pressure';%'traction';

%Specifying dimensions and number of elements
pointSpacing=1;
inputStruct.cylRadius=30;
inputStruct.numRadial=round((inputStruct.cylRadius*pi)/pointSpacing);
inputStruct.cylHeight=3;
inputStruct.numHeight=round(inputStruct.cylHeight/pointSpacing);
inputStruct.meshType='tri';
inputStruct.closeOpt=1;

% Derive patch data for a cylinder
[Fs,Vs,Cs]=patchcylinder(inputStruct);

%Material parameter set
c1=1e-3; %Shear-modulus-like parameter
m1=8; %Material parameter setting degree of non-linearity
k_factor=1e2; %Bulk modulus factor
k=c1*k_factor; %Bulk modulus

% FEA control settings
numTimeSteps=10; %Number of time steps desired
max_refs=25; %Max reforms
max_ups=0; %Set to zero to use full-Newton iterations
opt_iter=6; %Optimum number of iterations
max_retries=5; %Maximum number of retires
dtmin=(1/numTimeSteps)/100; %Minimum time step size
dtmax=1/numTimeSteps; %Maximum time step size

runMode='external';% 'internal' or 'external'

Creating model geometry and mesh

The disc is meshed using tetrahedral elements using tetgen

inputStruct.stringOpt='-pq1.2AaY';
inputStruct.Faces=Fs;
inputStruct.Nodes=Vs;
inputStruct.holePoints=[];
inputStruct.faceBoundaryMarker=Cs; %Face boundary markers
inputStruct.regionPoints=getInnerPoint(Fs,Vs); %region points
inputStruct.regionA=tetVolMeanEst(Fs,Vs); %Volume for regular tets
inputStruct.minRegionMarker=2; %Minimum region marker
[meshStruct]=runTetGen(inputStruct); % Mesh model using tetrahedral elements using tetGen

 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- TETGEN Tetrahedral meshing --- 20-Apr-2023 10:40:55
 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- Writing SMESH file --- 20-Apr-2023 10:40:55
----> Adding node field
----> Adding facet field
----> Adding holes specification
----> Adding region specification
--- Done --- 20-Apr-2023 10:40:55
--- Running TetGen to mesh input boundary--- 20-Apr-2023 10:40:55
Opening /mnt/data/MATLAB/GIBBON/data/temp/temp.smesh.
Delaunizing vertices...
Delaunay seconds:  0.033457
Creating surface mesh ...
Surface mesh seconds:  0.002375
Recovering boundaries...
Boundary recovery seconds:  0.006551
Removing exterior tetrahedra ...
Spreading region attributes.
Exterior tets removal seconds:  0.000892
Recovering Delaunayness...
Delaunay recovery seconds:  0.015868
Refining mesh...
  2442 insertions, added 1067 points, 174 tetrahedra in queue.
  813 insertions, added 37 points, 0 tetrahedra in queue.
Refinement seconds:  0.034217
Smoothing vertices...
Mesh smoothing seconds:  0.036142
Improving mesh...
Mesh improvement seconds:  0.002512

Writing /mnt/data/MATLAB/GIBBON/data/temp/temp.1.node.
Writing /mnt/data/MATLAB/GIBBON/data/temp/temp.1.ele.
Writing /mnt/data/MATLAB/GIBBON/data/temp/temp.1.face.
Writing /mnt/data/MATLAB/GIBBON/data/temp/temp.1.edge.

Output seconds:  0.026898
Total running seconds:  0.159093

Statistics:

  Input points: 1832
  Input facets: 3660
  Input segments: 5490
  Input holes: 0
  Input regions: 1

  Mesh points: 2936
  Mesh tetrahedra: 11933
  Mesh faces: 25696
  Mesh faces on exterior boundary: 3660
  Mesh faces on input facets: 3660
  Mesh edges on input segments: 5490
  Steiner points inside domain: 1104

--- Done --- 20-Apr-2023 10:40:56
 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- Importing TetGen files --- 20-Apr-2023 10:40:56
--- Done --- 20-Apr-2023 10:40:56

Access model element and patch data

Fb=meshStruct.facesBoundary;
Cb=meshStruct.boundaryMarker;
V=meshStruct.nodes;
CE=meshStruct.elementMaterialID;
E=meshStruct.elements;

Plotting model boundary surfaces and a cut view

hFig=cFigure;
subplot(1,2,1); hold on;
title('Model boundary surfaces and labels','FontSize',fontSize);
gpatch(Fb,V,Cb,'k',faceAlpha1);
colormap(gjet(6)); icolorbar;
axisGeom(gca,fontSize);

hs=subplot(1,2,2); hold on;
title('Cut view of solid mesh','FontSize',fontSize);
optionStruct.hFig=[hFig hs];
meshView(meshStruct,optionStruct);
axisGeom(gca,fontSize);
drawnow;

Defining the boundary conditions

The visualization of the model boundary shows colors for each side of the disc. These labels can be used to define boundary conditions.

%Define supported node sets
bcSupportList=unique(Fb(Cb==1,:)); %Node set part of selected face

%Define pressure surface
F_pressure=fliplr(Fb(Cb==2,:)); %The top face set

Visualizing boundary conditions. Markers plotted on the semi-transparent model denote the nodes in the various boundary condition lists.

hf=cFigure;
title('Boundary conditions','FontSize',fontSize);
xlabel('X','FontSize',fontSize); ylabel('Y','FontSize',fontSize); zlabel('Z','FontSize',fontSize);
hold on;

gpatch(Fb,V,'kw','none',0.5);

hl(1)=plotV(V(bcSupportList,:),'k.','MarkerSize',markerSize);
hl(2)=gpatch(F_pressure,V,'r','k',1);
patchNormPlot(F_pressure,V);
legend(hl,{'BC full support','Pressure surface'});

axisGeom(gca,fontSize);
camlight headlight;
drawnow;

Defining the FEBio input structure

See also febioStructTemplate and febioStruct2xml and the FEBio user manual.

%Get a template with default settings
[febio_spec]=febioStructTemplate;

%febio_spec version
febio_spec.ATTR.version='4.0';

%Module section
febio_spec.Module.ATTR.type='solid';

%Control section
febio_spec.Control.analysis='STATIC';
febio_spec.Control.time_steps=numTimeSteps;
febio_spec.Control.step_size=1/numTimeSteps;
febio_spec.Control.solver.max_refs=max_refs;
febio_spec.Control.solver.qn_method.max_ups=max_ups;
febio_spec.Control.time_stepper.dtmin=dtmin;
febio_spec.Control.time_stepper.dtmax=dtmax;
febio_spec.Control.time_stepper.max_retries=max_retries;
febio_spec.Control.time_stepper.opt_iter=opt_iter;

%Material section
materialName1='Material1';
febio_spec.Material.material{1}.ATTR.name=materialName1;
febio_spec.Material.material{1}.ATTR.type='Ogden';
febio_spec.Material.material{1}.ATTR.id=1;
febio_spec.Material.material{1}.c1=c1;
febio_spec.Material.material{1}.m1=m1;
febio_spec.Material.material{1}.c2=c1;
febio_spec.Material.material{1}.m2=-m1;
febio_spec.Material.material{1}.k=k;

%Mesh section
% -> Nodes
febio_spec.Mesh.Nodes{1}.ATTR.name='nodeSet_all'; %The node set name
febio_spec.Mesh.Nodes{1}.node.ATTR.id=(1:size(V,1))'; %The node id's
febio_spec.Mesh.Nodes{1}.node.VAL=V; %The nodel coordinates

% -> Elements
partName1='Part1';
febio_spec.Mesh.Elements{1}.ATTR.name=partName1; %Name of this part
febio_spec.Mesh.Elements{1}.ATTR.type='tet4'; %Element type
febio_spec.Mesh.Elements{1}.elem.ATTR.id=(1:1:size(E,1))'; %Element id's
febio_spec.Mesh.Elements{1}.elem.VAL=E; %The element matrix

% -> Surfaces
surfaceName1='LoadedSurface';
febio_spec.Mesh.Surface{1}.ATTR.name=surfaceName1;
febio_spec.Mesh.Surface{1}.tri3.ATTR.id=(1:1:size(F_pressure,1))';
febio_spec.Mesh.Surface{1}.tri3.VAL=F_pressure;

% -> NodeSets
nodeSetName1='bcSupportList';
febio_spec.Mesh.NodeSet{1}.ATTR.name=nodeSetName1;
febio_spec.Mesh.NodeSet{1}.VAL=mrow(bcSupportList);

%MeshDomains section
febio_spec.MeshDomains.SolidDomain.ATTR.name=partName1;
febio_spec.MeshDomains.SolidDomain.ATTR.mat=materialName1;

%Boundary condition section
% -> Fix boundary conditions
febio_spec.Boundary.bc{1}.ATTR.name='FixedDisplacement01';
febio_spec.Boundary.bc{1}.ATTR.type='zero displacement';
febio_spec.Boundary.bc{1}.ATTR.node_set=nodeSetName1;
febio_spec.Boundary.bc{1}.x_dof=1;
febio_spec.Boundary.bc{1}.y_dof=1;
febio_spec.Boundary.bc{1}.z_dof=1;

%Loads section
% -> Surface load
switch loadType
    case 'pressure'
        febio_spec.Loads.surface_load{1}.ATTR.type='pressure';
        febio_spec.Loads.surface_load{1}.ATTR.surface=surfaceName1;
        febio_spec.Loads.surface_load{1}.pressure.ATTR.lc=1;
        febio_spec.Loads.surface_load{1}.pressure.VAL=appliedPressure;
        febio_spec.Loads.surface_load{1}.symmetric_stiffness=1;
    case 'traction'
        febio_spec.Loads.surface_load{1}.ATTR.type='traction';
        febio_spec.Loads.surface_load{1}.ATTR.surface=surfaceName1;
        febio_spec.Loads.surface_load{1}.scale.ATTR.lc=1;
        febio_spec.Loads.surface_load{1}.scale.VAL=appliedPressure;
        febio_spec.Loads.surface_load{1}.traction=[0 0 -1];
end

%LoadData section
% -> load_controller
febio_spec.LoadData.load_controller{1}.ATTR.name='LC_1';
febio_spec.LoadData.load_controller{1}.ATTR.id=1;
febio_spec.LoadData.load_controller{1}.ATTR.type='loadcurve';
febio_spec.LoadData.load_controller{1}.interpolate='LINEAR';
%febio_spec.LoadData.load_controller{1}.extend='CONSTANT';
febio_spec.LoadData.load_controller{1}.points.pt.VAL=[0 0; 1 1];

%Output section
% -> log file
febio_spec.Output.logfile.ATTR.file=febioLogFileName;
febio_spec.Output.logfile.node_data{1}.ATTR.file=febioLogFileName_disp;
febio_spec.Output.logfile.node_data{1}.ATTR.data='ux;uy;uz';
febio_spec.Output.logfile.node_data{1}.ATTR.delim=',';

febio_spec.Output.logfile.element_data{1}.ATTR.file=febioLogFileName_stress;
febio_spec.Output.logfile.element_data{1}.ATTR.data='s1';
febio_spec.Output.logfile.element_data{1}.ATTR.delim=',';

febio_spec.Output.plotfile.compression=0;

Quick viewing of the FEBio input file structure

The febView function can be used to view the xml structure in a MATLAB figure window.

febView(febio_spec); %Viewing the febio file

Exporting the FEBio input file

Exporting the febio_spec structure to an FEBio input file is done using the febioStruct2xml function.

febioStruct2xml(febio_spec,febioFebFileName); %Exporting to file and domNode
% febView(febioFebFileName);

Running the FEBio analysis

To run the analysis defined by the created FEBio input file the runMonitorFEBio function is used. The input for this function is a structure defining job settings e.g. the FEBio input file name. The optional output runFlag informs the user if the analysis was run succesfully.

febioAnalysis.run_filename=febioFebFileName; %The input file name
febioAnalysis.run_logname=febioLogFileName; %The name for the log file
febioAnalysis.disp_on=1; %Display information on the command window
febioAnalysis.runMode=runMode;

[runFlag]=runMonitorFEBio(febioAnalysis);%START FEBio NOW!!!!!!!!

 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
-------->    RUNNING/MONITORING FEBIO JOB    <-------- 20-Apr-2023 10:41:02
FEBio path: /home/kevin/FEBioStudio2/bin/febio4
# Attempt removal of existing log files                20-Apr-2023 10:41:02
 * Removal succesful                                   20-Apr-2023 10:41:02
# Attempt removal of existing .xplt files              20-Apr-2023 10:41:02
 * Removal succesful                                   20-Apr-2023 10:41:02
# Starting FEBio...                                    20-Apr-2023 10:41:02
  Max. total analysis time is: Inf s
 * Waiting for log file creation                       20-Apr-2023 10:41:02
   Max. wait time: 30 s
 * Log file found.                                     20-Apr-2023 10:41:02
# Parsing log file...                                  20-Apr-2023 10:41:02
    number of iterations   : 9                         20-Apr-2023 10:41:03
    number of reformations : 9                         20-Apr-2023 10:41:03
------- converged at time : 0.1                        20-Apr-2023 10:41:03
    number of iterations   : 5                         20-Apr-2023 10:41:03
    number of reformations : 5                         20-Apr-2023 10:41:03
------- converged at time : 0.181833                   20-Apr-2023 10:41:03
    number of iterations   : 4                         20-Apr-2023 10:41:04
    number of reformations : 4                         20-Apr-2023 10:41:04
------- converged at time : 0.2654                     20-Apr-2023 10:41:04
    number of iterations   : 4                         20-Apr-2023 10:41:04
    number of reformations : 4                         20-Apr-2023 10:41:04
------- converged at time : 0.352254                   20-Apr-2023 10:41:04
    number of iterations   : 4                         20-Apr-2023 10:41:04
    number of reformations : 4                         20-Apr-2023 10:41:04
------- converged at time : 0.441737                   20-Apr-2023 10:41:04
    number of iterations   : 4                         20-Apr-2023 10:41:05
    number of reformations : 4                         20-Apr-2023 10:41:05
------- converged at time : 0.533323                   20-Apr-2023 10:41:05
    number of iterations   : 4                         20-Apr-2023 10:41:05
    number of reformations : 4                         20-Apr-2023 10:41:05
------- converged at time : 0.626592                   20-Apr-2023 10:41:05
    number of iterations   : 4                         20-Apr-2023 10:41:05
    number of reformations : 4                         20-Apr-2023 10:41:05
------- converged at time : 0.721208                   20-Apr-2023 10:41:05
    number of iterations   : 4                         20-Apr-2023 10:41:06
    number of reformations : 4                         20-Apr-2023 10:41:06
------- converged at time : 0.8169                     20-Apr-2023 10:41:06
    number of iterations   : 3                         20-Apr-2023 10:41:06
    number of reformations : 3                         20-Apr-2023 10:41:06
------- converged at time : 0.913454                   20-Apr-2023 10:41:06
    number of iterations   : 3                         20-Apr-2023 10:41:06
    number of reformations : 3                         20-Apr-2023 10:41:06
------- converged at time : 1                          20-Apr-2023 10:41:06
 Elapsed time : 0:00:04                                20-Apr-2023 10:41:06
 N O R M A L   T E R M I N A T I O N
# Done                                                 20-Apr-2023 10:41:06
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%

Import FEBio results

if runFlag==1 %i.e. a succesful run

Importing nodal displacements from a log file

    dataStruct=importFEBio_logfile(fullfile(savePath,febioLogFileName_disp),0,1);

    %Access data
    N_disp_mat=dataStruct.data; %Displacement
    timeVec=dataStruct.time; %Time

    %Create deformed coordinate set
    V_DEF=N_disp_mat+repmat(V,[1 1 size(N_disp_mat,3)]);

Plotting the simulated results using anim8 to visualize and animate deformations

    DN_magnitude=sqrt(sum(N_disp_mat(:,:,end).^2,2)); %Current displacement magnitude

    % Create basic view and store graphics handle to initiate animation
    hf=cFigure; %Open figure
    gtitle([febioFebFileNamePart,': Press play to animate']);
    title('Displacement magnitude [mm]','Interpreter','Latex')
    hp=gpatch(Fb,V_DEF(:,:,end),DN_magnitude,'k',1); %Add graphics object to animate
    hp.Marker='.';
    hp.MarkerSize=markerSize2;
    hp.FaceColor='interp';

    axisGeom(gca,fontSize);
    colormap(gjet(250)); colorbar;
    caxis([0 max(DN_magnitude)]);
    axis(axisLim(V_DEF)); %Set axis limits statically
    camlight headlight;

    % Set up animation features
    animStruct.Time=timeVec; %The time vector
    for qt=1:1:size(N_disp_mat,3) %Loop over time increments
        DN_magnitude=sqrt(sum(N_disp_mat(:,:,qt).^2,2)); %Current displacement magnitude

        %Set entries in animation structure
        animStruct.Handles{qt}=[hp hp]; %Handles of objects to animate
        animStruct.Props{qt}={'Vertices','CData'}; %Properties of objects to animate
        animStruct.Set{qt}={V_DEF(:,:,qt),DN_magnitude}; %Property values for to set in order to animate
    end
    anim8(hf,animStruct); %Initiate animation feature
    drawnow;

Importing element stress from a log file

    dataStruct=importFEBio_logfile(fullfile(savePath,febioLogFileName_stress),0,1);

    %Access data
    E_stress_mat=dataStruct.data;

    E_stress_mat(isnan(E_stress_mat))=0;

Plotting the simulated results using anim8 to visualize and animate deformations

    [CV]=faceToVertexMeasure(E,V,E_stress_mat(:,:,end));

    % Create basic view and store graphics handle to initiate animation
    hf=cFigure; %Open figure
    gtitle([febioFebFileNamePart,': Press play to animate']);
    title('$\sigma_{1}$ [MPa]','Interpreter','Latex')
    hp=gpatch(Fb,V_DEF(:,:,end),CV,'k',1); %Add graphics object to animate
    hp.Marker='.';
    hp.MarkerSize=markerSize2;
    hp.FaceColor='interp';

    axisGeom(gca,fontSize);
    colormap(gjet(250)); colorbar;
    caxis([min(E_stress_mat(:)) max(E_stress_mat(:))]/3);
    axis(axisLim(V_DEF)); %Set axis limits statically
    camlight headlight;

    % Set up animation features
    animStruct.Time=timeVec; %The time vector
    for qt=1:1:size(N_disp_mat,3) %Loop over time increments

        [CV]=faceToVertexMeasure(E,V,E_stress_mat(:,:,qt));

        %Set entries in animation structure
        animStruct.Handles{qt}=[hp hp]; %Handles of objects to animate
        animStruct.Props{qt}={'Vertices','CData'}; %Properties of objects to animate
        animStruct.Set{qt}={V_DEF(:,:,qt),CV}; %Property values for to set in order to animate
    end
    anim8(hf,animStruct); %Initiate animation feature
    drawnow;

end

GIBBON www.gibboncode.org

Kevin Mattheus Moerman, [email protected]

GIBBON footer text

License: https://github.com/gibbonCode/GIBBON/blob/master/LICENSE

GIBBON: The Geometry and Image-based Bioengineering add-On. A toolbox for image segmentation, image-based modeling, meshing, and finite element analysis.

This program is free software: you can redistribute it and/or modify it under the terms of the GNU General Public License as published by the Free Software Foundation, either version 3 of the License, or (at your option) any later version.

This program is distributed in the hope that it will be useful, but WITHOUT ANY WARRANTY; without even the implied warranty of MERCHANTABILITY or FITNESS FOR A PARTICULAR PURPOSE. See the GNU General Public License for more details.

You should have received a copy of the GNU General Public License along with this program. If not, see http://www.gnu.org/licenses/.