DEMO_febio_0074_vertebrae_compression_01

Below is a demonstration for:

Building triangulated surface geometry for a spine segment
Defining the boundary conditions
Coding the febio structure
Running the model
Importing and visualizing results

Keywords
Control parameters
Get vertebra bone model
Get vertebra bone model
Remeshing
Find top and bottom surface
Define boundary conditions
Defining the FEBio input structure
Quick viewing of the FEBio input file structure
Exporting the FEBio input file
Running the FEBio analysis
Import FEBio results

Keywords

febio_spec version 4.0
febio, FEBio
spine, vertebra, disc
contact, sliding, friction
tetrahedral elements, tet4
hexahedral elements, hex8
static, solid
hyperelastic, Ogden
displacement logfile

clear; close all; clc;

Plot settings

fontSize=15;
faceAlpha1=1;
faceAlpha2=0.3;
markerSize1=25;
markerSize2=10;
lineWidth=2;
cMap=spectral(250);

Control parameters

% Path names
defaultFolder = fileparts(fileparts(mfilename('fullpath')));
savePath=fullfile(defaultFolder,'data','temp');

% Defining file names
febioFebFileNamePart='tempModel';
febioFebFileName=fullfile(savePath,[febioFebFileNamePart,'.feb']); %FEB file name
febioLogFileName=fullfile(savePath,[febioFebFileNamePart,'.txt']); %FEBio log file name
febioLogFileName_disp=[febioFebFileNamePart,'_disp_out.txt']; %Log file name for exporting displacement
febioLogFileName_stress=[febioFebFileNamePart,'_stress_out.txt']; %Log file name for exporting stress
febioLogFileName_stress_prin=[febioFebFileNamePart,'_stress_prin_out.txt']; %Log file name for exporting principal stress

%Geometric parameters
pointSpacing=3; %Approximate/desired node spacing
volumeFactorDisc=2;

%Material parameter set
E_youngs1=0.1; %Material Young's modulus MPa
nu1=0.4; %Material Poisson's ratio

% FEA control settings
numTimeSteps=10; %Number of time steps desired
max_refs=25; %Max reforms
max_ups=0; %Set to zero to use full-Newton iterations
opt_iter=6; %Optimum number of iterations
max_retries=5; %Maximum number of retires
dtmin=(1/numTimeSteps)/100; %Minimum time step size
dtmax=1/numTimeSteps; %Maximum time step size
runMode='external';

%Boundary condition parameters
displacementMagnitude=-1;

Get vertebra bone model

[Fd,Vd]=graphicsModels('vertebra');
rotAngle=-6;
R=euler2DCM([0 (rotAngle./180)*pi 0]);
Vd=Vd*R;

Get vertebra bone model

[Fd,Vd]=graphicsModels('vertebra');
rotAngle=-6;
R=euler2DCM([0 (rotAngle./180)*pi 0]);
Vd=Vd*R;

Remeshing

optionStructRemesh.pointSpacing=pointSpacing; %Set desired point spacing
optionStructRemesh.disp_on=1; % Turn off command window text display
[Fd,Vd]=ggremesh(Fd,Vd,optionStructRemesh);

 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
------>  Geogram/vorpalite for resmeshing  <------ 01-May-2023 10:56:54
# Export mesh input file.                          01-May-2023 10:56:54
# Run Geomgram/vorpalite.                          01-May-2023 10:56:54
 ______________________________________________________________________________ 
|                                                                              |
| o-[config      ] Configuration file name:geogram.ini                         |
|                  Home directory:/home/kevin                                  |
| o-[I/O         ] Output = /home/kevin/GIBBON/data/temp/temp_out.obj          |
|                  Loading file /home/kevin/GIBBON/data/temp/temp.obj...       |
|                  (FP64) nb_v:7500 nb_e:0 nb_f:15000 nb_b:0 tri:1 dim:3       |
|                  Attributes on vertices: point[3]                            |
| o-[Load        ] Elapsed time: 0 s                                           |
   ___________________________
 _/ =====[preprocessing]===== \________________________________________________
|                                                                              |
| o-[CmdLine     ] using pre:epsilon=0(0%)                                     |
|                  using pre:max_hole_area=100                                 |
|                  using pre:min_comp_area=369.182(3%)                         |
| o-[Components  ] Nb connected components=1                                   |
|                  Mesh does not have small connected component (good)         |
| o-[Validate    ] Mesh does not have 0-area facets (good)                     |
| o-[CmdLine     ] using pre:margin=0(0%)                                      |
| o-[Pre         ] Elapsed time: 0 s                                           |
   _______________________
 _/ =====[remeshing]===== \____________________________________________________
|                                                                              |
||| o-[Newton      ] Elapsed time: 0.08s                                         |
| o-[Remesh      ] Computing RVD...                                            |
| o-[Validate    ] (FP64) nb_v:1580 nb_e:0 nb_f:3160 nb_b:0 tri:1 dim:3        |
|                  Attributes on vertices: point[3]                            |
| o-[Remesh      ] Elapsed time: 0.24 s                                        |
   ____________________________
 _/ =====[postprocessing]===== \_______________________________________________
|                                                                              |
| o-[CmdLine     ] using post:min_comp_area=369.659(3%)                        |
| o-[Components  ] Nb connected components=1                                   |
|                  Mesh does not have small connected component (good)         |
| o-[CmdLine     ] using post:max_hole_area=100                                |
|                  using post:max_deg3_dist=0.122828(0.10000000000000001%)     |
| o-[Degree3     ] Does not have any degree 3 vertex (good)                    |
| o-[Post        ] Elapsed time: 0 s                                           |
   ____________________
 _/ =====[result]===== \_______________________________________________________
|                                                                              |
| o-[FinalMesh   ] (FP64) nb_v:1580 nb_e:0 nb_f:3160 nb_b:0 tri:1 dim:3        |
|                  Attributes on vertices: point[3]                            |
| o-[I/O         ] Saving file /home/kevin/GIBBON/data/temp/temp_out.obj...    |
| o-[Total time  ] Elapsed time: 0.28 s                                        |
\______________________________________________________________________________/
# Importing remeshed geometry.                     01-May-2023 10:56:54
# Removing temporary files.                        01-May-2023 10:56:54
# Done!                                            01-May-2023 10:56:54

Find top and bottom surface

The below is a very basic hardcoded approach to finding (approximately) the top and bottom surfaces where the intevertebral discs would attached to the vertebra. The "detection" is based on the angle elements face with respect to the z-axis, and the distance from the origin (which lies in the middle in terms of the z-direction and in the centre of the disc attachement area in terms of the xy-direction).

angularThreshold=(25/180)*pi;
distanceThreshold=26;

VdF=patchCentre(Fd,Vd);

N=patchNormal(Fd,Vd);
nz=[0 0 1];
a=acos(dot(N,nz(ones(size(N,1),1),:),2));

D             = sqrt(sum(VdF(:,[1 2]).^2,2));
logicTop      = D<distanceThreshold & a<angularThreshold;
indNotInLogic = unique(Fd(~logicTop,:));
logicTop      = logicTop & ~any(ismember(Fd,indNotInLogic),2);
logicTop      = triSurfLogicSharpFix(Fd,logicTop,3);

D             = sqrt(sum(VdF(:,[1 2]).^2,2));
logicBottom   = D<distanceThreshold & a>(pi-angularThreshold);
indNotInLogic = unique(Fd(~logicBottom,:));
logicBottom   = logicBottom & ~any(ismember(Fd,indNotInLogic),2);
logicBottom   = triSurfLogicSharpFix(Fd,logicBottom,3);

Cd=zeros(size(Fd,1),1);
Cd(logicTop)=1;
Cd(logicBottom)=2;

Eb1=patchBoundary(Fd(Cd==1,:));
indList1=edgeListToCurve(Eb1);
indList1=indList1(1:end-1);

Eb2=patchBoundary(Fd(Cd==2,:));
indList2=edgeListToCurve(Eb2);
indList2=indList2(1:end-1);

n=[numel(indList1) numel(indList2)];
[nMax,indMax]=max(n);
nn=abs(diff(n));
switch indMax
    case 1
        [Fd,Vd,Eb2,Cd]=triSurfSplitBoundary(Fd,Vd,Eb2,size(Eb2,1)+nn,Cd);
        indList2=edgeListToCurve(Eb2);
        indList2=indList2(1:end-1);
    case 2
        [Fd,Vd,Eb1,Cd]=triSurfSplitBoundary(Fd,Vd,Eb1,size(Eb1,1)+nn,Cd);
        indList1=edgeListToCurve(Eb1);
        indList1=indList1(1:end-1);
end

cFigure; hold on;
gpatch(Fd,Vd,Cd,'k',1);

axisGeom(gca,fontSize);
colormap gjet; icolorbar;
camlight('headlight');
gdrawnow;

nc=10;
ns=50;
[Vd]=smoothCurve(Fd,Vd,nc,ns,indList1);
[Vd]=smoothCurve(Fd,Vd,nc,ns,indList2);

cFigure; hold on;
gpatch(Fd,Vd,Cd,'k',1);
% patchNormPlot(F1,V1)
plotV(Vd(indList1,:),'r.-','MarkerSize',25,'LineWidth',3);
plotV(Vd(indList2,:),'r.-','MarkerSize',25,'LineWidth',3);

plotV(Vd(indList1(1:2),:),'y.','MarkerSize',35);
plotV(Vd(indList2(1:2),:),'y.','MarkerSize',35);

axisGeom(gca,fontSize);
colormap gjet; icolorbar;
camlight('headlight');
gdrawnow;

Define region points

[V_region]=getInnerPoint(Fd,Vd);

cFigure; hold on;
gpatch(Fd,Vd,'w','none',0.5);
plotV(V_region,'r.','markerSize',25);
axisGeom(gca,fontSize);
camlight('headlight');
gdrawnow;

Mesh using tetgen

inputStruct.stringOpt='-pq1.2AaY'; %TetGen option string
inputStruct.Faces=Fd; %The faces
inputStruct.Nodes=Vd; %The vertices
inputStruct.holePoints=[]; %The hole interior points
inputStruct.faceBoundaryMarker=Cd; %Face boundary markers
inputStruct.regionPoints=V_region; %The region interior points
inputStruct.regionA=tetVolMeanEst(Fd,Vd)*volumeFactorDisc; %Volume for regular tets

Mesh model using tetrahedral elements using tetGen

[meshOutput]=runTetGen(inputStruct); %Run tetGen

 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- TETGEN Tetrahedral meshing --- 01-May-2023 10:57:00
 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- Writing SMESH file --- 01-May-2023 10:57:00
----> Adding node field
----> Adding facet field
----> Adding holes specification
----> Adding region specification
--- Done --- 01-May-2023 10:57:00
--- Running TetGen to mesh input boundary--- 01-May-2023 10:57:00
Opening /home/kevin/GIBBON/data/temp/temp.smesh.
Delaunizing vertices...
Delaunay seconds:  0.004296
Creating surface mesh ...
Surface mesh seconds:  0.001219
Recovering boundaries...
Boundary recovery seconds:  0.002119
Removing exterior tetrahedra ...
Spreading region attributes.
Exterior tets removal seconds:  0.001387
Recovering Delaunayness...
Delaunay recovery seconds:  0.001009
Refining mesh...
Refinement seconds:  0.02213
Smoothing vertices...
Mesh smoothing seconds:  0.041555
Improving mesh...
Mesh improvement seconds:  0.001754

Writing /home/kevin/GIBBON/data/temp/temp.1.node.
Writing /home/kevin/GIBBON/data/temp/temp.1.ele.
Writing /home/kevin/GIBBON/data/temp/temp.1.face.
Writing /home/kevin/GIBBON/data/temp/temp.1.edge.

Output seconds:  0.007945
Total running seconds:  0.083509

Statistics:

  Input points: 1584
  Input facets: 3168
  Input segments: 4752
  Input holes: 0
  Input regions: 1

  Mesh points: 3561
  Mesh tetrahedra: 16716
  Mesh faces: 35016
  Mesh faces on exterior boundary: 3168
  Mesh faces on input facets: 3168
  Mesh edges on input segments: 4752
  Steiner points inside domain: 1977

--- Done --- 01-May-2023 10:57:00
 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- Importing TetGen files --- 01-May-2023 10:57:00
--- Done --- 01-May-2023 10:57:00

Access model element and patch data

Fb=meshOutput.facesBoundary; %Boundary faces of the disc
Cb=meshOutput.boundaryMarker; %Boundary marker/color data for the disc
V=meshOutput.nodes; %The vertices/nodes
E=meshOutput.elements; %The tet4 elements

Visualizing mesh using meshView, see also anim8

meshView(meshOutput);

Define boundary conditions

logicTopFaces= (Cb==1);
logicBottomFaces= (Cb==2);

bcPrescribeList=unique(Fb(logicTopFaces,:));
bcSupportList=unique(Fb(logicBottomFaces,:));

Visualize BC's

cFigure; hold on;
title('Boundary conditions');
hp(1)=gpatch(Fb,V,'w','none',0.5);
hp(2)=plotV(V(bcSupportList,:),'k.','MarkerSize',25);
hp(3)=plotV(V(bcPrescribeList,:),'r.','MarkerSize',25);
legend(hp,{'Disc','Constrained nodes','Applied displacement nodes'});

axisGeom;
camlight headlight;
gdrawnow;

Defining the FEBio input structure

See also febioStructTemplate and febioStruct2xml and the FEBio user manual.

%Get a template with default settings
[febio_spec]=febioStructTemplate;

%febio_spec version
febio_spec.ATTR.version='4.0';

%Module section
febio_spec.Module.ATTR.type='solid';

%Control section
febio_spec.Control.analysis='STATIC';
febio_spec.Control.time_steps=numTimeSteps;
febio_spec.Control.step_size=1/numTimeSteps;
febio_spec.Control.solver.max_refs=max_refs;
febio_spec.Control.solver.qn_method.max_ups=max_ups;
febio_spec.Control.time_stepper.dtmin=dtmin;
febio_spec.Control.time_stepper.dtmax=dtmax;
febio_spec.Control.time_stepper.max_retries=max_retries;
febio_spec.Control.time_stepper.opt_iter=opt_iter;

%Material section
materialName1='Material1';
febio_spec.Material.material{1}.ATTR.name=materialName1;
febio_spec.Material.material{1}.ATTR.type='neo-Hookean';
febio_spec.Material.material{1}.ATTR.id=1;
febio_spec.Material.material{1}.E=E_youngs1;
febio_spec.Material.material{1}.v=nu1;

% Mesh section
% -> Nodes
febio_spec.Mesh.Nodes{1}.ATTR.name='Object1'; %The node set name
febio_spec.Mesh.Nodes{1}.node.ATTR.id=(1:size(V,1))'; %The node id's
febio_spec.Mesh.Nodes{1}.node.VAL=V; %The nodel coordinates

% -> Elements
partName1='Part1';
febio_spec.Mesh.Elements{1}.ATTR.name=partName1; %Name of this part
febio_spec.Mesh.Elements{1}.ATTR.type='tet4'; %Element type
febio_spec.Mesh.Elements{1}.elem.ATTR.id=(1:1:size(E,1))'; %Element id's
febio_spec.Mesh.Elements{1}.elem.VAL=E; %The element matrix

% -> NodeSets
nodeSetName1='bcSupportList';
nodeSetName2='bcPrescribeList';

febio_spec.Mesh.NodeSet{1}.ATTR.name=nodeSetName1;
febio_spec.Mesh.NodeSet{1}.VAL=mrow(bcSupportList);

febio_spec.Mesh.NodeSet{2}.ATTR.name=nodeSetName2;
febio_spec.Mesh.NodeSet{2}.VAL=mrow(bcPrescribeList);

%MeshDomains section
febio_spec.MeshDomains.SolidDomain.ATTR.name=partName1;
febio_spec.MeshDomains.SolidDomain.ATTR.mat=materialName1;

%Boundary condition section
% -> Fix boundary conditions
febio_spec.Boundary.bc{1}.ATTR.name='zero_displacement_xyz';
febio_spec.Boundary.bc{1}.ATTR.type='zero displacement';
febio_spec.Boundary.bc{1}.ATTR.node_set=nodeSetName1;
febio_spec.Boundary.bc{1}.x_dof=1;
febio_spec.Boundary.bc{1}.y_dof=1;
febio_spec.Boundary.bc{1}.z_dof=1;

febio_spec.Boundary.bc{2}.ATTR.name='zero_displacement_xy';
febio_spec.Boundary.bc{2}.ATTR.type='zero displacement';
febio_spec.Boundary.bc{2}.ATTR.node_set=nodeSetName2;
febio_spec.Boundary.bc{2}.x_dof=1;
febio_spec.Boundary.bc{2}.y_dof=1;
febio_spec.Boundary.bc{2}.z_dof=0;

febio_spec.Boundary.bc{3}.ATTR.name='prescibed_displacement_z';
febio_spec.Boundary.bc{3}.ATTR.type='prescribed displacement';
febio_spec.Boundary.bc{3}.ATTR.node_set=nodeSetName2;
febio_spec.Boundary.bc{3}.dof='z';
febio_spec.Boundary.bc{3}.value.ATTR.lc=1;
febio_spec.Boundary.bc{3}.value.VAL=displacementMagnitude;
febio_spec.Boundary.bc{3}.relative=0;

%LoadData section
% -> load_controller
febio_spec.LoadData.load_controller{1}.ATTR.id=1;
febio_spec.LoadData.load_controller{1}.ATTR.type='loadcurve';
febio_spec.LoadData.load_controller{1}.interpolate='LINEAR';
febio_spec.LoadData.load_controller{1}.points.point.VAL=[0 0; 1 1];

%Output section
% -> log file
febio_spec.Output.logfile.ATTR.file=febioLogFileName;
febio_spec.Output.logfile.node_data{1}.ATTR.file=febioLogFileName_disp;
febio_spec.Output.logfile.node_data{1}.ATTR.data='ux;uy;uz';
febio_spec.Output.logfile.node_data{1}.ATTR.delim=',';

febio_spec.Output.logfile.element_data{1}.ATTR.file=febioLogFileName_stress;
febio_spec.Output.logfile.element_data{1}.ATTR.data='sz';
febio_spec.Output.logfile.element_data{1}.ATTR.delim=',';

febio_spec.Output.logfile.element_data{2}.ATTR.file=febioLogFileName_stress_prin;
febio_spec.Output.logfile.element_data{2}.ATTR.data='s1;s2;s3';
febio_spec.Output.logfile.element_data{2}.ATTR.delim=',';

% Plotfile section
febio_spec.Output.plotfile.compression=0;

Quick viewing of the FEBio input file structure

The febView function can be used to view the xml structure in a MATLAB figure window.

febView(febio_spec); %Viewing the febio file

Exporting the FEBio input file

Exporting the febio_spec structure to an FEBio input file is done using the febioStruct2xml function.

febioStruct2xml(febio_spec,febioFebFileName); %Exporting to file and domNode
%system(['gedit ',febioFebFileName,' &']);

Running the FEBio analysis

To run the analysis defined by the created FEBio input file the runMonitorFEBio function is used. The input for this function is a structure defining job settings e.g. the FEBio input file name. The optional output runFlag informs the user if the analysis was run succesfully.

febioAnalysis.run_filename=febioFebFileName; %The input file name
febioAnalysis.run_logname=febioLogFileName; %The name for the log file
febioAnalysis.disp_on=1; %Display information on the command window
febioAnalysis.runMode=runMode;
febioAnalysis.maxLogCheckTime=10; %Max log file checking time

[runFlag]=runMonitorFEBio(febioAnalysis);%START FEBio NOW!!!!!!!!

 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
-------->    RUNNING/MONITORING FEBIO JOB    <-------- 01-May-2023 10:57:04
FEBio path: /home/kevin/FEBioStudio/bin/febio4
# Attempt removal of existing log files                01-May-2023 10:57:04
 * Removal succesful                                   01-May-2023 10:57:04
# Attempt removal of existing .xplt files              01-May-2023 10:57:04
 * Removal succesful                                   01-May-2023 10:57:04
# Starting FEBio...                                    01-May-2023 10:57:04
  Max. total analysis time is: Inf s
 * Waiting for log file creation                       01-May-2023 10:57:04
   Max. wait time: 10 s
 * Log file found.                                     01-May-2023 10:57:04
# Parsing log file...                                  01-May-2023 10:57:04
    number of iterations   : 3                         01-May-2023 10:57:05
    number of reformations : 3                         01-May-2023 10:57:05
------- converged at time : 0.1                        01-May-2023 10:57:05
    number of iterations   : 3                         01-May-2023 10:57:05
    number of reformations : 3                         01-May-2023 10:57:05
------- converged at time : 0.2                        01-May-2023 10:57:05
    number of iterations   : 3                         01-May-2023 10:57:05
    number of reformations : 3                         01-May-2023 10:57:05
------- converged at time : 0.3                        01-May-2023 10:57:05
    number of iterations   : 3                         01-May-2023 10:57:05
    number of reformations : 3                         01-May-2023 10:57:05
------- converged at time : 0.4                        01-May-2023 10:57:05
    number of iterations   : 3                         01-May-2023 10:57:06
    number of reformations : 3                         01-May-2023 10:57:06
------- converged at time : 0.5                        01-May-2023 10:57:06
    number of iterations   : 3                         01-May-2023 10:57:06
    number of reformations : 3                         01-May-2023 10:57:06
------- converged at time : 0.6                        01-May-2023 10:57:06
    number of iterations   : 3                         01-May-2023 10:57:06
    number of reformations : 3                         01-May-2023 10:57:06
------- converged at time : 0.7                        01-May-2023 10:57:06
    number of iterations   : 3                         01-May-2023 10:57:06
    number of reformations : 3                         01-May-2023 10:57:06
------- converged at time : 0.8                        01-May-2023 10:57:06
    number of iterations   : 3                         01-May-2023 10:57:06
    number of reformations : 3                         01-May-2023 10:57:06
------- converged at time : 0.9                        01-May-2023 10:57:06
    number of iterations   : 3                         01-May-2023 10:57:07
    number of reformations : 3                         01-May-2023 10:57:07
------- converged at time : 1                          01-May-2023 10:57:07
 Elapsed time : 0:00:02                                01-May-2023 10:57:07
 N O R M A L   T E R M I N A T I O N
# Done                                                 01-May-2023 10:57:07
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%

Import FEBio results

if runFlag==1 %i.e. a succesful run

Importing nodal displacements from a log file

    dataStruct=importFEBio_logfile(fullfile(savePath,febioLogFileName_disp),0,1);

    %Access data
    N_disp_mat=dataStruct.data; %Displacement
    timeVec=dataStruct.time; %Time

    %Create deformed coordinate set
    V_DEF=N_disp_mat+repmat(V,[1 1 size(N_disp_mat,3)]);

Plotting the simulated results using anim8 to visualize and animate deformations

    DN_magnitude=sqrt(sum(N_disp_mat(:,:,end).^2,2)); %Current displacement magnitude

    % Create basic view and store graphics handle to initiate animation
    hf=cFigure; %Open figure
    gtitle([febioFebFileNamePart,': Press play to animate']);
    title('Displacement magnitude [mm]','Interpreter','Latex')
    hp=gpatch(Fb,V_DEF(:,:,end),DN_magnitude,'k',1,2); %Add graphics object to animate
    hp.Marker='.';
    hp.MarkerSize=markerSize2;
    hp.FaceColor='interp';
    gpatch(Fb,V,0.5*ones(1,3),'none',0.25); %A static graphics object

    axisGeom(gca,fontSize);
    colormap(cMap); colorbar;
    caxis([0 max(DN_magnitude)]); caxis manual;
    axis(axisLim(V_DEF)); %Set axis limits statically
    view(140,30);
    camlight headlight;

    % Set up animation features
    animStruct.Time=timeVec; %The time vector
    for qt=1:1:size(N_disp_mat,3) %Loop over time increments
        DN_magnitude=sqrt(sum(N_disp_mat(:,:,qt).^2,2)); %Current displacement magnitude

        %Set entries in animation structure
        animStruct.Handles{qt}=[hp hp]; %Handles of objects to animate
        animStruct.Props{qt}={'Vertices','CData'}; %Properties of objects to animate
        animStruct.Set{qt}={V_DEF(:,:,qt),DN_magnitude}; %Property values for to set in order to animate
    end
    anim8(hf,animStruct); %Initiate animation feature
    drawnow;

Importing element stress from a log file

    dataStruct=importFEBio_logfile(fullfile(savePath,febioLogFileName_stress_prin),0,1);

    %Access data
    E_stress_mat=dataStruct.data(:,3,:);

Plotting the simulated results using anim8 to visualize and animate deformations

    [CV]=faceToVertexMeasure(E,V,E_stress_mat(:,:,end));

    % Create basic view and store graphics handle to initiate animation
    hf=cFigure; %Open figure  /usr/local/MATLAB/R2020a/bin/glnxa64/jcef_helper: symbol lookup error: /lib/x86_64-linux-gnu/libpango-1.0.so.0: undefined symbol: g_ptr_array_copy

    gtitle([febioFebFileNamePart,': Press play to animate']);
    title('$\sigma_{3}$ [MPa]','Interpreter','Latex')
    hp=gpatch(Fb,V_DEF(:,:,end),CV,'k',1,2); %Add graphics object to animate
    hp.Marker='.';
    hp.MarkerSize=markerSize2;
    hp.FaceColor='interp';
    gpatch(Fb,V,0.5*ones(1,3),'none',0.25); %A static graphics object

    axisGeom(gca,fontSize);
    colormap(cMap); colorbar;
    caxis([min(E_stress_mat(:)) max(E_stress_mat(:))]);
    axis(axisLim(V_DEF)); %Set axis limits statically
    view(140,30);
    camlight headlight;

    % Set up animation features
    animStruct.Time=timeVec; %The time vector
    for qt=1:1:size(N_disp_mat,3) %Loop over time increments

        [CV]=faceToVertexMeasure(E,V,E_stress_mat(:,:,qt));

        %Set entries in animation structure
        animStruct.Handles{qt}=[hp hp]; %Handles of objects to animate
        animStruct.Props{qt}={'Vertices','CData'}; %Properties of objects to animate
        animStruct.Set{qt}={V_DEF(:,:,qt),CV}; %Property values for to set in order to animate
    end
    anim8(hf,animStruct); %Initiate animation feature
    drawnow;

end

function [V1]=smoothCurve(F1,V1,nc,ns,indList1)
clear cPar
cPar.n=nc;
cPar.Method='HC';
e=[(1:numel(indList1))' [(2:numel(indList1))';1]];
v=V1(indList1,:);
[v]=patchSmooth(e,v,[],cPar);
V1(indList1,:)=v;

indTouch=unique(F1(any(ismember(F1,indList1),2),:));
indTouch=unique(F1(any(ismember(F1,indTouch),2),:));
logicRigid=true(size(V1,1),1);
logicRigid(indTouch)=0;
logicRigid(indList1)=1;
indRigid=find(logicRigid);

cPar.n=ns;
cPar.Method='HC';
cPar.RigidConstraints=indRigid;
[V1]=patchSmooth(F1,V1,[],cPar);
end

GIBBON www.gibboncode.org

Kevin Mattheus Moerman, [email protected]

GIBBON footer text

License: https://github.com/gibbonCode/GIBBON/blob/master/LICENSE

GIBBON: The Geometry and Image-based Bioengineering add-On. A toolbox for image segmentation, image-based modeling, meshing, and finite element analysis.

This program is free software: you can redistribute it and/or modify it under the terms of the GNU General Public License as published by the Free Software Foundation, either version 3 of the License, or (at your option) any later version.

This program is distributed in the hope that it will be useful, but WITHOUT ANY WARRANTY; without even the implied warranty of MERCHANTABILITY or FITNESS FOR A PARTICULAR PURPOSE. See the GNU General Public License for more details.

You should have received a copy of the GNU General Public License along with this program. If not, see http://www.gnu.org/licenses/.

DEMO_febio_0074_vertebrae_compression_01

Contents

Keywords

Control parameters

Get vertebra bone model

Get vertebra bone model

Remeshing

Find top and bottom surface

Define boundary conditions

Defining the FEBio input structure

Quick viewing of the FEBio input file structure

Exporting the FEBio input file

Running the FEBio analysis

Import FEBio results